HEIDENHAIN iTNC 530 (340 49x-01) ISO programming - Manual (Page 319)

HEIDENHAIN iTNC 530 319
8.4 Cy
cles f
o
r Milling P
o
c
k
ets, St
uds and Slots
8 Set-up clearance Q200 (incremental value): Distance
between tool tip and workpiece surface.
8 Depth Q201 (incremental value): Distance between
workpiece surface and bottom of stud.
8 Feed rate for plunging Q206: Traversing speed of
the tool in mm/min when moving to depth. If you are
plunge-cutting into the material, enter a low value; if
you have already cleared the stud, enter a higher feed
rate.
8 Plunging depth Q202 (incremental value): Infeed per
cut. Enter a value greater than 0.
8 Feed rate for milling Q207: Traversing speed of the
tool in mm/min while milling.
8 Workpiece surface coordinate Q203 (absolute
value): Coordinate of the workpiece surface.
8 2nd set-up clearance Q204 (incremental value):
Coordinate in the tool axis at which no collision
between tool and workpiece (clamping devices) can
occur.
8 Center in 1st axis Q216 (absolute value): Center of
the stud in the reference axis of the working plane.
8 Center in 2nd axis Q217 (absolute value): Center of
the stud in the minor axis of the working plane.
8 First side length Q218 (incremental value): Length
of stud parallel to the reference axis of the working
plane.
8 Second side length Q219 (incremental value): Length
of stud parallel to the secondary axis of the working
plane.
8 Corner radius Q220: Radius of the stud corner.
8 Allowance in 1st axis Q221 (incremental value):
Allowance for pre-positioning in the reference axis of
the working plane referenced to the length of the
stud.
Example: NC blocks
N350 G213 STUD FINISHING
Q200=2 ;SET-UP CLEARANCE
Q291=-20 ;DEPTH
Q206=150 ;FEED RATE FOR PLUNGING
Q202=5 ;PLUNGING DEPTH
Q207=500 ;FEED RATE FOR MILLING
Q203=+30 ;SURFACE COORDINATE
Q294=50 ;2ND SET-UP CLEARANCE
Q216=+50 ;CENTER IN 1ST AXIS
Q217=+50 ;CENTER IN 2ND AXIS
Q218=80 ;FIRST SIDE LENGTH
Q219=60 ;SECOND SIDE LENGTH
Q220=5 ;CORNER RADIUS
Q221=0 ;OVERSIZE